Process

When the cycle is selected, a single escape movement is executed. Depending on the reference cycle, certain input parameters are required in order to execute the escape movement from the current position.

"SysDrillTapping” reference cycle - Thread tapping

The thread tapping drill is retracted from the current Z position by the specified value for the return distance (@P4), taking into account the pitch (@P7) and the spindle speed for thread tapping (@P24). The spindle rotation direction results from the thread type (@P18) and takes place in the opposite rotation direction of the interrupted cycle.

To ensure correct execution, the parameters @P7, @P18, @P24 and @P4 should be assigned the same values as the interrupted cycle.

Notice

In order to use a thread tapping and milling cycle without compensation chuck, it is necessary for technological reasons for the spindle to be operated as a position-controlled spindle since it is positioned internally in the cycle before thread tapping and is operated as a path axis.

"SysDrillThreadMilling” reference cycle - Drill thread milling

First, the tool is retracted to the drilling centre (@P40, @P41) before starting a retraction in Z.

Here, the values for @P40 and @P41 must be identical to the values of the interrupted cycle. It is also necessary to call the cycle in the same coordinate system (NOV, #CD, etc.) as the interrupted cycle to ensure that the drilling centre is approached correctly.

"SysDrill" reference cycle - General drilling cycle

Retract mode for the remaining drilling cycles. Here, the tool in Z is retracted by the specified value for the return distance (@P4).